Skip to content
M
MakerStage

Tolerancing is one of the highest-cost decisions you make on a titanium drawing. Unlike aluminum, where a shop can routinely hold ±0.001 in. with minimal process overhead, titanium requires extra effort at every tight-tolerance feature: slower finish passes, in-process gauging, carefully controlled coolant, and sharp tooling that must be replaced more frequently.

The goal of this guide is to help you distinguish between tolerances that are functionally necessary (bearing bores, sealing surfaces, mating interfaces) and those that are accidentally tight (title block defaults applied to features that don't need them). The second category is the most common source of avoidable cost in titanium parts.

Key Takeaway

Specify tolerances based on function, not habit. Every ±0.001 in. callout on a non-critical feature adds inspection time and process cost in titanium. Use standard title block tolerances everywhere the assembly doesn't require more.

Tolerance Standards

Titanium Tolerancing: Key Principles

Tolerances on titanium parts must be specified deliberately. Unlike aluminum, where achieving ±0.001 in. is routine, titanium’s poor thermal conductivity, work hardening, and elastic modulus characteristics make tight tolerances expensive to hold. The three principles for tolerancing titanium: specify only what is functionally required, tolerance at standard grades where possible (ISO 286, ASME Y14.5-2018), and flag precision features explicitly rather than using blanket title block tolerances.

Thermal Challenge

CTE of 4.8 µin./in.·°F means a 20°F workpiece temperature rise introduces 96 µin. error in a 1 in. feature. Finish machining and measurement must occur at equilibrium temperature (68°F / 20°C per ISO 1).

Springback Effect

Ti-6Al-4V elastic modulus (16 Msi / 110 GPa) is lower than steel (29 Msi / 200 GPa) and causes measurable springback in thin walls and thin floors. Design walls ≥ 0.060 in. (1.5 mm) and floors ≥ 0.050 in. (1.27 mm) to prevent elastic distortion.

BUE and Surface

Built-up edge (BUE) at low SFM degrades surface finish unpredictably. Recommend operating at 80–120 SFM (24–37 m/min) with sharp TiAlN-coated carbide, preventing BUE and delivering Ra 32–63 µin. (0.8–1.6 µm) consistently.

Achievable Tolerances

CNC Titanium Tolerance Ranges

CNC machined titanium achievable tolerance ranges
TierTolerance (in.)Tolerance (mm)ProcessCost PremiumNotes
Standard±0.005±0.133-axis mill / lathe1× (baseline)Default title block tolerance; no special process controls required
Precision±0.002±0.05Mill + in-process gauging1.5–2×Requires thermal control and fresh tooling for finish cuts
High Precision±0.001±0.025Mill + CMM feedback2–3×Workpiece must equilibrate to 68°F; multiple finishing passes
Ultra-Precision±0.0005±0.013Jig bore / precision grind5–10×Achievable only on selected features; requires specialized equipment
Bore (H7 fit)+0.0010/−0.0000+0.025/−0.000Boring + reaming2–4×Reamed bores in Ti-6Al-4V; recommend carbide reamers with flood coolant
Press fit boreIT6 classISO 286Precision boring3–5×Interference fits in titanium require careful analysis — low E causes higher deflection
Feature-Specific Tolerances

Tolerances by Feature Type

Titanium CNC tolerances by feature type
FeatureStandard Tol.Achievable Tol.Key Constraints
Linear dimension±0.005 in.±0.001 in.Thermal equilibrium critical; multi-pass finishing required
Hole diameter (drilled)+0.003/−0.000 in.+0.001/−0.000 in.BUE causes bore oversize; use carbide drill, flood coolant
Bore (reamed)H8 (IT8)H7 (IT7)Carbide reamer, 30–50 SFM, high-pressure coolant through-tool
OD turned±0.003 in.±0.0005 in.Tailstock support for L/D > 3; finish passes at low DOC
Thread pitch diameter2B class3B classTi threads gall easily; use TiCN-coated tap, tapping fluid
Flatness0.005 in./6 in.0.001 in./6 in.Requires grinding; milled flatness limited by thermal distortion
Parallelism0.005/6 in.0.002/6 in.Multiple-fixturing; datum reference critical
Position (bolt pattern)Ø0.010 in.Ø0.003 in.CMM verification required; thermal equilibration before measurement
Surface finish Ra125 µin. (3.2 µm)16–32 µin. (0.4–0.8 µm)Achieved with finishing carbide; Ra ≤ 8 µin. requires grinding
GD&T for Titanium

GD&T Recommendations for Titanium Parts

Per ASME Y14.5-2018 (ISO 1101 equivalent), apply GD&T controls to titanium parts following these guidelines to maximize manufacturability and inspection efficiency.

⬛

Flatness

Specify flatness per zone (e.g., 0.003/6 in.) not global. Grinding required for ≤ 0.001 in. flatness. Milled flatness limited to 0.002–0.005 in. due to fixturing distortion.

⊕

Position (True Position)

Use Ø0.005 in. for standard drilled patterns; Ø0.003 in. for precision dowel locations. Add MMC modifier to bonus tolerance where fit allows. CMM measurement required for Ø ≤ 0.005 in.

🔵

Cylindricity

Achievable cylindricity: 0.001–0.003 in. for turned bores. Specify form tolerance separately from size tolerance to avoid overconstraining. Titanium OD turning achieves Cyl. 0.001 in. with support.

⊥

Perpendicularity

Milled features perpendicularity: 0.002–0.005 in. per 6 in. height. Use datum hierarchy correctly — primary (flatness), secondary (position), tertiary (perpendicularity). Avoid redundant datums on cast-to-forge transitions.

↺

Runout / Total Runout

Turned circular features: total runout 0.002–0.003 in. achievable. Journals requiring ≤ 0.001 in. runout need precision cylindrical grinding. Apply datum on shortest feasible bearing span.

〰️

Surface Texture

Call out Ra per ASME B46.1 or ISO 4287. For titanium: Ra 125 µin. (milled), Ra 63 µin. (finish milled), Ra 32 µin. (fine finish), Ra 8–16 µin. (ground). Specify lay direction only if functionally required — it adds cost.

DFM Rules

DFM Rules for Tolerancing Titanium Parts

1. Default to ±0.005 in. where functionally acceptable

Standard title block tolerances of ±0.005 in. (±0.13 mm) are easily achievable in titanium. Only tighten where function requires — each step tighter increases cost 1.5–3×.

2. Specify precision tolerances only on mating features

Tight tolerances belong only on bores, pins, locating surfaces, and seating faces. Non-functional dimensions (pocket depths, non-mating walls) should use standard tolerances.

3. Use consistent datum references

Define datums (ASME Y14.5 DRF) consistently across all views and features. Inconsistent datums force the machinist to re-set-up the part, multiplying setup cost and risk.

4. Allow thermal equilibration before final measurement

Specify "Inspect at 68°F ± 2°F (20°C ± 1°C)" on all precision features per ISO 1. Do not specify tolerances without inspection temperature if they are tighter than ±0.002 in.

5. Do not tolerance to fit a standard fastener

Use clearance holes for titanium bolted joints (≥ D+0.015 in.) with free-fit tolerances (H11). Precision-located bolted joints should use dowels for position, bolts for clamping only.

6. Flag inspection method on precision features

Specify CMM or functional gauge on features ≤ ±0.002 in. Coordinate measuring machines (CMM) per ISO 10360 with probe qualification are required for reliable measurement at this level.

Common Questions

Frequently Asked Questions

What is a tolerance, and why does it matter for machined parts?
A tolerance is the permissible range of dimensional variation for a feature — the difference between the maximum and minimum acceptable size. Example: a shaft with a nominal diameter of 0.500 in. and a tolerance of ±0.001 in. must measure between 0.499 in. and 0.501 in. for the part to be accepted. Tolerances matter because no machining process produces a perfectly exact dimension — tools flex, workpieces expand with heat, spindles have runout. The engineer's job is to specify tolerances that are functionally necessary (tight enough for the assembly to work, loose enough to be manufacturable at reasonable cost). Tighter tolerances always cost more. In titanium specifically, they can cost significantly more than in aluminum due to springback, thermal expansion during cutting, and BUE at the tool tip.
What does "title block tolerance" mean on a drawing?
A title block tolerance is a default tolerance that applies to all dimensions on an engineering drawing unless a tighter or looser value is explicitly called out. Common title block tolerance format: ±0.010 in. for one decimal place (e.g., 1.5 in.), ±0.005 in. for two decimal places (e.g., 1.50 in.), ±0.001 in. for three decimal places (e.g., 1.500 in.). For titanium parts, this matters because designers sometimes apply blanket tight tolerances (three decimal places on all dimensions) without realizing that every tight-tolerance feature requires additional inspection time and process care — driving up cost significantly. Best practice: explicitly specify only the tolerances that functional assembly requires, and leave the rest at standard title block values.
What tolerances can CNC machining achieve in titanium?
CNC machined titanium parts can achieve three levels of dimensional accuracy: Standard tolerances (±0.005 in. / ±0.13 mm) are achievable routinely on 3-axis mills and lathes without special process controls. Precision tolerances (±0.001–0.002 in. / ±0.025–0.05 mm) require controlled cutting conditions, in-process gauging, and fine-tuning of thermal compensation. Ultra-precision tolerances (±0.0005 in. / ±0.013 mm) require specialized equipment (jig boring, precision grinding, coordinate measuring machine feedback loops) and are achievable only on selected feature types. Achieving tighter tolerances in titanium is more challenging than aluminum because titanium's low thermal conductivity causes workpiece temperature rise during cutting, which introduces dimensional variation.
How does titanium's thermal expansion affect machining tolerances?
Titanium's CTE (Coefficient of Thermal Expansion) is approximately 4.8 µin./in.·°F (8.6 µm/m·°C) — roughly 60% of aluminum's (13.1 µin./in.·°F) but similar to steel (~6.3 µin./in.·°F). This means a 1 in. titanium feature changes 4.8 µin. for every 1°F of temperature change. For a precision bore (±0.001 in. tolerance), a 20°F temperature change in the workpiece during machining would introduce ~96 µin. of dimensional error — nearly the full tolerance band. Best practices: allow titanium workpieces to equilibrate to room temperature (68°F / 20°C per ISO 1) before final measurement and before finishing cuts.
What surface finish can titanium achieve after CNC machining?
CNC milled Ti-6Al-4V achieves: rough milling Ra 125–250 µin. (3.2–6.3 µm); semi-finish Ra 63–125 µin. (1.6–3.2 µm); finish milling Ra 32–63 µin. (0.8–1.6 µm); fine finishing Ra 16–32 µin. (0.4–0.8 µm). CNC turned titanium achieves: roughing Ra 63–125 µin.; finishing Ra 16–32 µin.; fine turning Ra 8–16 µin. Post-machining processes: grinding to Ra 4–8 µin. (0.1–0.2 µm); lapping to Ra 1–4 µin. (0.025–0.1 µm); electropolishing for biomedical applications to Ra ≤ 4 µin. (0.1 µm).
Why are tight tolerances on titanium more expensive than on aluminum?
Several factors make tight tolerances more expensive in titanium than aluminum: (1) Temperature variation — titanium's poor thermal conductivity requires slower finish passes, more frequent tool pauses, and coolant flood to prevent workpiece thermal growth. (2) Tool deflection — titanium's high strength requires carbide tooling and more conservative parameters, reducing chip load and feed rate in finish passes. (3) BUE (built-up edge) — titanium's chemical affinity for carbide causes BUE at low cutting speeds, degrading surface finish unpredictably; requires sharp tooling with frequent changes. (4) Springback — titanium's elasticity (E = 16 Msi / 110 GPa vs. 10 Msi / 69 GPa for Al) causes wall springback after thin-wall milling; requires predictive DOC adjustments. (5) In-process gauging — precision titanium parts typically require 100% measurement during machining, adding 15–30% cycle time.

Related Resources

Titanium CNC Machining Guide
Grades, speeds, feeds, tooling, DFM, cost
Wall Thickness Guidelines
Minimum walls, floors, ribs for titanium DFM
Surface Finishes for Titanium
Ra values, anodize, passivation, electropolish

Quote Precision Titanium Parts

MakerStage sources CNC machined titanium parts to ±0.001 in. tolerances from vetted precision shops. Upload your STEP file for competitive quotes with CMM inspection options.

Get a Free Titanium Quote